GATE Production and Industrial Engineering (PI): Machining, Non-Traditional Machining, CNC and Robotics (Merchant's circle, cutting force and specific energy, Taylor tool life, machining time, indexing, thread cutting, grinding, ECM, LBM, CNC interpolation, robot transforms), previous-year questions solved

Every Manufacturing Processes II question from the GATE PI papers of 2024, 2025 and 2026, solved: Merchant's circle, cutting force from specific energy, Taylor tool life, turning and drilling time, indexing, thread cutting, grinding, ECM and laser machining, CNC interpolation, CAD formats and robot transforms. Every answer matches the official key and was recomputed in code from the paper's numbers.

Questions from official GATE PI papers (IISc Bengaluru 2024, IIT Roorkee 2025, IIT Guwahati 2026); solutions by Skill-Lync. · Updated 19 Nov 2026 · 24 questions

GATE 2024 · PI · Q.55NAT · 2 marksMetal cutting: forces, tool life, tool materials and machining time

Turning a 160 mm diameter, 190 mm long bar at 80 pi m/min and 0.2 mm/rev: machining time in minutes

The following data are given in relation to turning operation of a cylindrical workpiece.
Diameter of the workpiece = 160 mm, length of the workpiece = 190 mm, cutting velocity = m/min, and tool feed = 0.2 mm/rev.
Assuming the approach and the overrun of the tool to be 5 mm each, the machining time (in minutes) is __________ . (Answer in integer)

Answer: 2 min Official key: 2 to 2

  1. In straight turning the tool moves along the bar at mm for every revolution, so the time is the distance the tool travels divided by the feed speed (mm per minute). The tool travels the bar length plus the approach (run-in before it touches the work) and the overrun (run-out after it leaves).
  2. Spindle speed from cutting speed: , so rev/min.
  3. Tool travel mm. Feed speed mm/min.
  4. Time 2 min, equal to the key 2 to 2.

Check: the cutting speed is given in m/min, so it was converted to mm/min before dividing by the circumference. Trap: leaving out the approach and the overrun gives min, which is not an integer answer and does not match the key.

Where this shows up in industry

Process planners add approach and overrun (often 2 to 5 mm) to every cut when they estimate cycle time for a turned shaft, and cycle time feeds straight into the quoted price per part. On a CNC lathe the same time is read from feed speed along the programmed tool path.

GATE 2024 · PI · Q.58NAT · 2 marksMetal cutting: forces, tool life, tool materials and machining time

Orthogonal turning: 2 m/s, 0.2 mm/rev, 2 mm depth, 2 J/mm3 specific energy: main cutting force in N

During orthogonal turning, the cutting speed, feed and depth of cut are set as 2 m/s, 0.2 mm/rev and 2 mm, respectively. The specific cutting energy (neglecting the effect of feed force on the total cutting power) is 2 J/mm. The main cutting force (in N) is __________ . (Answer in integer)

Answer: 800 N Official key: 800 to 800

  1. Specific cutting energy is the energy spent to remove one cubic millimetre of metal. Cutting power is , where MRR is the volume removed per second. Neglecting the feed force, all the power is the main cutting force working through the cutting speed: .
  2. MRR in mm and s: m/s mm/s, so MRR mm/s.
  3. J/s W.
  4. 800 N, equal to the key 800 to 800.

Check: the same answer comes from mm N, since 1 J/mm is 1000 N/mm and the chip cross-section is mm. The cutting speed cancels out. Trap: stopping at the power, 1600 W, or mixing m/s and mm/s.

Where this shows up in industry

Machinists check that a roughing pass is within the spindle power by multiplying the specific cutting energy of the work material (about 2 to 3 J per mm3 for steel) by the removal rate. The main cutting force also sets the clamping force and the deflection of a slender shaft.

GATE 2025 · PI · Q.30NAT · 1 markMetal cutting: forces, tool life, tool materials and machining time

Chip width in orthogonal straight turning with 0.5 mm depth of cut and zero ASA side cutting edge angle

In an orthogonal straight turning process, the feed is 0.1 mm/rev and the depth of cut is 0.5 mm. In ASA system, the side cutting edge angle of the cutting tool is . The width (in mm) of the chip is________. (Rounded off to one decimal place)

Answer: 0.5 mm Official key: 0.5 to 0.5

  1. The chip width is the length of the cutting edge in contact with the work, measured along the edge. The uncut chip thickness is measured at right angles to it.
  2. In ASA the side cutting edge angle is measured from the tool axis. The depth of cut is measured along the radius, so and .
  3. With the cutting edge lies square to the feed direction, which is the orthogonal case: mm and mm.
  4. Check with the ORS approach angle : mm, the same.

Trap: 0.1 mm is the uncut chip thickness (feed), not the width. The width equals the depth of cut when the edge is square to the feed.

Where this shows up in industry

Programmers pick the depth of cut and feed so that chip width and thickness stay within what the insert can carry. A lead (side cutting edge) angle spreads the same cut over a longer edge, which thins the chip and lowers the load per unit edge length.

GATE 2025 · PI · Q.50NAT · 2 marksMetal cutting: forces, tool life, tool materials and machining time

Total time to drill one 10 mm through hole in 30 mm mild steel plate at 600 rpm and 0.3 mm/rev

A through hole of 10 mm diameter is to be drilled in a mild steel plate of 30 mm thickness. The selected spindle speed and feed for drilling hole are 600 revolutions per minute (RPM) and 0.3 mm/rev, respectively. Take initial approach and breakthrough distances as 3 mm each. The total time (in minute) for drilling one hole is________. (Rounded off to two decimal places)

Answer: 0.20 min Official key: 0.19 to 0.21

  1. Machining time = tool travel / feed rate. The drill must travel the plate thickness plus the approach before it touches the work plus the breakthrough distance (the drill point must come out through the far side).
  2. Travel mm.
  3. Feed rate mm/min.
  4. min.

Trap: leaving out the approach and breakthrough gives min, outside the key range. The 3 mm breakthrough is about the length of a 118 degree drill point on a 10 mm drill ( mm), which is why it is included.

Where this shows up in industry

Cycle-time estimates for drilling always add the rapid approach and the drill point length before the full-diameter section leaves the hole. Drilling cycles in CNC controls, such as G81, take a clearance plane and a depth that already include these allowances.

GATE 2025 · PI · Q.52NAT · 2 marksMetal cutting: forces, tool life, tool materials and machining time

Friction coefficient on the rake face from 900 N cutting and 275 N thrust force with 10 degree rake

During orthogonal cutting with a tool of rake angle, the cutting and thrust forces are 900 N and 275 N, respectively. The coefficient of friction on the rake surface of the tool is________. (Rounded off to two decimal places)

Answer: 0.51 Official key: 0.49 to 0.53

  1. Merchant's circle: the force of the chip on the tool splits into a friction force along the rake face and a normal force to it, or into the cutting force (along the cutting velocity) and the thrust force (across it). The friction coefficient is , where is the friction angle.
  2. Resolving and along and across the rake face (rake angle , positive): and , so .
  3. Numbers: , so .
  4. Check by angles: , so and , inside the key range 0.49 to 0.53.

Trap: using the sign of a negative rake, , gives 0.12. The friction angle is the rake angle plus the angle of the resultant to the cutting direction.

Where this shows up in industry

Tool dynamometer readings of cutting and thrust force are turned into a friction coefficient this way to compare coatings and coolants. A low value on the rake face means thinner chips, lower power and less built-up edge.

GATE 2026 · PI · Q.33NAT · 1 markMetal cutting: forces, tool life, tool materials and machining time

Feed ratio f1/f2 from modified Taylor equation with n = 0.25, m = 0.5 and V1/V2 = 2/3 at equal tool life

A modified Taylor tool life equation is given as follows:

where is the cutting speed (m/s), is the tool life in minutes and is the feed in mm/rev, and . Under two different cutting conditions and the tool life (, ) was found to be the same.

If the ratio of the cutting speeds used is 2/3, then the ratio of corresponding feeds must be ______ (rounded off to two decimal places).

Answer: 2.25 Official key: 2.2 to 2.3

  1. Rule: the modified Taylor equation says that the product is the same for every pair of cutting conditions that wears the tool at the same rate. Two conditions that give the same tool life therefore have the same , and it cancels.
  2. Write the equation for both conditions: , so . The exponent is not needed.
  3. Rearrange: .
  4. , so the answer is 2.25.

Check: slower cutting ( is two thirds of ) allows a coarser feed at the same tool life, so must be larger than 1. Substituting back into the equation gives the same constant for both conditions (1.6870 and 1.6870). Common slips: using the exponent gives 1.22; inverting the speed ratio gives 0.44.

Where this shows up in industry

Process planners use the extended Taylor equation to trade speed against feed on a turning or milling job: when the cutter must run slower, they raise the feed to keep the cycle time while holding the tool life that the insert budget allows.

GATE 2026 · PI · Q.47MSQ · 2 marksMetal cutting: forces, tool life, tool materials and machining time

How the constant C in the shear angle relation depends on normal stress on the shear plane

In the theory of orthogonal machining, assuming that the shear plane will take up an angle that minimizes energy, the shear angle can be shown to be

where is the shear angle, the rake angle, and the friction angle.

Which ONE or MORE among the following is/are TRUE?

  1. (A) is constant if the shear stress on the shear plane is independent of the normal stress.
  2. (B) is constant if the shear stress on the shear plane is dependent on the normal stress.
  3. (C) depends on material properties if the shear stress on the shear plane is independent of the normal stress.
  4. (D) depends on material properties if the shear stress on the shear plane is linearly dependent on the normal stress.

Answer: (A) and (D) Official key: A;D

  1. Rule: Merchant assumes the shear plane settles at the angle that needs the least cutting force. Two cases are taught. First theory: shear stress on the shear plane is a material constant, not affected by the normal stress. This gives , so the constant is for every material. Second theory: shear stress rises with normal stress, . This gives with , so the constant is , which depends on the material constant .
  2. (A) True. With no normal stress effect the constant is , the same for all materials, so it is constant.
  3. (B) False. With normal stress effect the constant moves with . From our minimisation of the cutting force: gives , gives , gives , gives .
  4. (C) False. With no normal stress effect there is no material constant left to depend on: stays .
  5. (D) True. With a linear dependence , depends on the material through . The answer is (A) and (D).

Check: for every rake angle (0 to 15 degrees) and friction angle (20 to 35 degrees) tried, the minimum-force shear angle gave the same for a fixed (spread below degrees), so depends only on the shear stress law, as the four statements assume. Note on the printed formula: textbooks write (a larger rake angle raises , a larger friction angle lowers it). The paper prints the signs of and the other way round, but the question only asks how behaves, and the key follows Merchant's two theories.

Where this shows up in industry

Shear angle theory underlies how tool makers choose rake angles: a positive rake and low friction (sharp edge, coated insert, good coolant) raise the shear angle, thin the chip and cut the cutting force and power in turning and milling.

GATE 2026 · PI · Q.51MSQ · 2 marksMetal cutting: forces, tool life, tool materials and machining time

Which work materials are NOT commonly machined using diamond cutting tools

Which ONE or MORE among the following work materials is/are NOT commonly machined using diamond cutting tools?
  1. (A)Mild steel
  2. (B)Stainless steel
  3. (C)Silicon
  4. (D)Aluminium alloy

Answer: (A) and (B) Official key: A;B

  1. Rule: diamond is pure carbon, the hardest tool material, and it keeps a very sharp edge. Its weakness is chemical. At cutting temperatures of roughly 700 °C or more, carbon dissolves into iron and reacts with it, so the diamond graphitises and wears away within minutes.
  2. Mild steel (A) and stainless steel (B) are iron-based, so they are not machined with diamond. They are cut with carbide, ceramic or CBN (cubic boron nitride) instead.
  3. Silicon (C) is machined with diamond: wafers and optical parts are single point diamond turned or ground. Aluminium alloy (D) is machined with diamond too, for mirror finishes on mirrors, drums and memory discs.
  4. The materials that are NOT diamond machined are (A) and (B), so the answer is (A) and (B).

Trap: the question asks for the materials NOT machined, so the set is the opposite of what diamond is good for. Remember the rule: diamond for non-ferrous metals, plastics, composites and ceramics; CBN for hardened and ferrous work. We stored each material as ferrous or not and tested the NOT set: (A) and (B).

Where this shows up in industry

Ultra-precision shops use single point diamond turning for aluminium optics, copper mirrors and silicon infrared lenses, and keep steel parts on carbide or CBN tooling because diamond fails quickly on iron.

GATE 2024 · PI · Q.18MCQ · 1 markMachine tools: lathe, milling, drilling and grinding

Simple indexing for 12 divisions on a dividing head: choose the crank rotation

To create 12 divisions on a disc by using simple indexing and dividing head on a horizontal milling machine, choose the correct option for the rotation of the crank pin.
  1. (A)3 full rotations and 5 holes on a 15-hole circle
  2. (B)5 full rotations and 4 holes on a 16-hole circle
  3. (C)3 full rotations and 5 holes on a 18-hole circle
  4. (D)5 full rotations and 4 holes on a 20-hole circle

Answer: (A) Official key: A

  1. Simple (plain) indexing turns the work through a fraction of a revolution by turning the crank of the dividing head. The head has a 40:1 worm drive: 40 turns of the crank turn the spindle once. So for equal divisions the crank turns times between cuts. The fractional part is set on the index plate by counting holes on a circle of the right size.
  2. For : turns, that is 3 full turns and one third of a turn.
  3. One third of a turn needs a hole circle whose hole count is a multiple of 3. A 15-hole circle works: , so 5 holes on the 15-hole circle.
  4. Option (A) is 3 turns and 5 holes on a 15-hole circle: (A).

Check: every option was turned into a number of turns with exact fractions and compared with . (A) gives 3 + 5/15 = 3.333. (B) gives 5 + 4/16 = 5.25, (C) gives 3 + 5/18 = 3.278 (18 is not a multiple of 3, so no hole count gives one third) and (D) gives 5 + 4/20 = 5.2. Trap: the 5 and 4 in options (B) and (D) are fractions of other divisions, such as 40/7 = 5 5/7 for 7 cuts; always divide 40 by the number of divisions first.

Where this shows up in industry

Tool rooms cut gears, splines, hexagon heads and ratchet teeth on a horizontal mill with a dividing head. The operator looks up the hole circle on the index plate and uses the sector arms to count the holes without losing place.

GATE 2024 · PI · Q.43MSQ · 2 marksMachine tools: lathe, milling, drilling and grinding

Eccentric hole on a disc using a lathe: which items are required (tool, chucks, drill bit)?

Choose the item(s) which is/are required to make an eccentric hole on a disc, as shown, using a lathe.
Disc with an eccentric hole: a circle with two dashed centre lines and a small hole above and to the left of the disc centreHoleDisc
  1. (A)Single point cutting tool
  2. (B)Four jaw chuck
  3. (C)Drill bit
  4. (D)Three jaw chuck

Answer: (B) and (C) Official key: B;C

  1. An eccentric hole is one whose axis is not on the axis of the disc. On a lathe, a hole is made along the spindle axis, so the job must be held with the required offset between the disc centre and the spindle centre.
  2. (D) Three jaw chuck: not needed. Its jaws move together and always centre the disc, so the hole would be at the centre.
  3. (B) Four jaw chuck: required. Its four jaws move independently, so the disc can be shifted and checked with a dial gauge until the marked hole position runs true on the spindle axis.
  4. (C) Drill bit: required, held in the tailstock or turret, to make the hole along the spindle axis.
  5. (A) Single point cutting tool: not required. It would be needed only to bore the drilled hole out to a larger size or to turn the outside, and the question asks only for the hole to be made.
  6. The required items are (B) and (C).

Check: each item was tested against two needs, setting the offset and cutting the hole, and only the four jaw chuck and the drill bit meet one each and are the minimum set. Trap: choosing the three jaw chuck because it is the usual lathe chuck; self-centring is the very thing that cannot give an eccentric hole.

Where this shows up in industry

Crank-like parts, eccentric cams, and bushings with an offset bore are set up in a four jaw chuck and clocked in with a dial test indicator before drilling or boring. Packing a thin shim under one jaw is a common shop way to set a small offset.

GATE 2025 · PI · Q.22MCQ · 1 markMachine tools: lathe, milling, drilling and grinding

Best process for an accurate 8 mm through hole in 30 mm mild steel plate with less time

A through hole of 8 mm diameter is to be drilled in a 30 mm thick mild steel plate. Which one of the following processes is the most appropriate to achieve high dimensional accuracy with less processing time?
  1. (A)Conventional drilling using a carbide drill bit
  2. (B)Die sinking EDM using a copper electrode
  3. (C)ECM using a copper electrode
  4. (D)Plasma arc machining

Answer: (A) Official key: A

  1. The question asks for two things at once, accuracy and short processing time, for a plain round hole in a soft, easily machined metal. The rule is to use the cheapest conventional process that meets the tolerance, and to go to a non-traditional process only when the material is too hard, the shape is not round, or the part is too delicate for cutting forces.
  2. Mild steel is easy to cut. A carbide drill at about 60 m/min and 0.15 mm/rev spins at about 2400 rpm and feeds at about 360 mm/min, so the 30 mm depth plus the drill point takes about 5 s. The hole size is set by the drill and is accurate enough for a general fit; a reamer can follow if needed.
  3. (B) Die sinking EDM is accurate, but the hole volume is about 1508 mm and a steel roughing rate of tens of mm/min makes it a matter of about 25 min, with an electrode to make and wear. (C) ECM is accurate and fast per unit volume, but needs a purpose-made insulated electrode, electrolyte handling and a high-current supply: far too much set-up for one plain hole. (D) Plasma arc machining is fast but leaves a tapered, rough cut and a heat affected zone, so it is not accurate.
  4. Only conventional drilling is both accurate enough and quickest, so the answer is (A).

Trap: non-traditional processes sound more precise, but they win only when the work material or the shape defeats a cutting tool.

Where this shows up in industry

Shops drill plain holes in steel plate with carbide or coated drills and follow with a reamer when a tighter size is needed. EDM and ECM are kept for hardened tool steel, odd-shaped holes and burr-free cross holes in finished parts.

GATE 2025 · PI · Q.31NAT · 1 markMachine tools: lathe, milling, drilling and grinding

Lead screw speed in rpm when cutting a double-start 3 mm pitch thread at 400 rpm spindle speed

The pitch of the single-start lead screw of a lathe is 6 mm. It is used to cut double start thread of 3 mm pitch on a cylindrical work piece. During the thread cutting, the spindle rotates at 400 revolutions per minute (RPM). The speed (in RPM) of the lead screw is________. (Answer in integer)

Answer: 400 rpm Official key: 399 to 401

  1. In thread cutting the carriage must move one lead of the thread for every turn of the work. For a multi-start thread, lead = number of starts pitch.
  2. Double start, 3 mm pitch: lead mm per spindle revolution.
  3. The carriage moves as the half nut rides on the lead screw. The single-start lead screw of 6 mm pitch advances 6 mm per lead screw revolution.
  4. Carriage travel per minute equals both: lead screw rpm , so the lead screw speed is 400 rpm.

Trap: using the 3 mm pitch as if it were the lead gives 200 rpm. A double-start thread advances twice its pitch per turn, so the lead screw must turn twice as fast as that slip.

Where this shows up in industry

A lathe set up for a multi-start thread uses change gears or a CNC spindle-synchronised feed set to the thread lead, not the pitch. Multi-start screws are used where fast travel per turn is needed, such as jar lids, valve stems and some lead screws themselves.

GATE 2025 · PI · Q.39MCQ · 2 marksMachine tools: lathe, milling, drilling and grinding

Match loading, glazing, dressing and truing of a grinding wheel with their definitions

Match the operation/phenomenon in a grinding process with the corresponding definition listed in the table.
Operation/phenomenonDefinition
PLoading1Regenerating the sharpness of the grinding wheel
QGlazing2Filling of grinding chips in the space between the abrasive grits
RDressing3Restoring the geometry/shape of the grinding wheel
STruing4Condition of dull grinding wheel with worn-out grains
  1. (A)P – 4, Q – 1, R – 3, S – 2
  2. (B)P – 2, Q – 3, R – 1, S – 4
  3. (C)P – 2, Q – 4, R – 1, S – 3
  4. (D)P – 4, Q – 3, R – 1, S – 2

Answer: (C) Official key: C

  1. Two are faults of the wheel and two are corrective operations.
  2. Loading is the fault where chips fill the space between the grits and the wheel stops cutting. P matches 2.
  3. Glazing is the grains wearing flat and dull, so the wheel face turns shiny and rubs instead of cutting. Q matches 4.
  4. Dressing is the operation that breaks away dull grains and loaded chips to expose fresh, sharp grits, so it regenerates sharpness. R matches 1.
  5. Truing is the operation that makes the wheel round and concentric again, or gives it a required profile, so it restores the geometry. S matches 3.
  6. P-2, Q-4, R-1, S-3 is option (C).

Trap: dressing and truing are often done with the same diamond tool, so they are confused. Truing fixes shape, dressing fixes sharpness.

Where this shows up in industry

Grinder operators dress a loaded or glazed wheel with a single-point or rotary diamond and true a new or crashed wheel to run concentric. Profile grinding of threads and gear teeth depends on a truing roll or CNC diamond dresser to put the form on the wheel.

GATE 2024 · PI · Q.59NAT · 2 marksNon-traditional machining: ECM, EDM, LBM and jets

Electrochemical machining of copper at 2 cm3/min: required current in A

Electro-chemical machining is performed on a flat copper workpiece. If the material removal rate is 2 cm/min throughout the process, then the required current (in A) is __________ . (Rounded off to 1 decimal place)
Copper properties: Melting point = 1085 °C, density = 9 g/cm, gram atomic weight = 63, and valency of dissolution = 2
Faraday’s constant = 96500 C
Stefan-Boltzmann constant = W/m-K

Answer: 919.0 A Official key: 915.0 to 925.0

  1. Faraday’s law of electrolysis: the mass dissolved is proportional to the charge passed. The mass removed per second is , with the gram atomic weight, the current, the valency of dissolution and Faraday’s constant. Each atom that leaves the work gives up electrons, and one mole of electrons carries 96500 C.
  2. Mass removal rate: g/s (2 cm/min is cm/s).
  3. Solve for the current: .
  4. 919.0 A, inside the key range 915.0 to 925.0.

Check: putting back gives g/s, the same . The melting point and the Stefan-Boltzmann constant are not needed (they are extra data that this question does not use). Trap: taking the valency as 1 gives 459.5 A, half the right value; the paper states valency 2 for copper going into solution as Cu.

Where this shows up in industry

ECM power supplies for turbine blades and gun-barrel rifling are sized from Faraday's law: the current needed rises in proportion to the removal rate, and the large currents of hundreds or thousands of amperes are why the supply and the busbars are heavy. Process engineers use the law to set the feed rate of the tool into the work.

GATE 2025 · PI · Q.38MCQ · 2 marksNon-traditional machining: ECM, EDM, LBM and jets

Match EDM, LBM, CHM and WJM with their machining features

Match the following with reference to the machining process and its feature.
ProcessFeature
PEDM1Loss of dimensional accuracy due to under cutting
QLBM2Cutting edible items
RCHM3Machining of a deep square blind hole on a mild steel plate
SWJM4High speed profile cutting on a thin mild steel plate
  1. (A)P – 3, Q – 4, R – 1, S – 2
  2. (B)P – 4, Q – 3, R – 2, S – 1
  3. (C)P – 4, Q – 2, R – 1, S – 3
  4. (D)P – 1, Q – 2, R – 3, S – 4

Answer: (A) Official key: A

  1. Match each process to the feature that follows from its mechanism.
  2. R, chemical machining (CHM): the etchant attacks the metal sideways under the edge of the mask as well as downward. This undercut makes the cut wider than the mask opening and costs dimensional accuracy. R matches 1.
  3. S, water jet machining (WJM): a cold water jet cuts soft materials such as food without heat, burning or contamination. S matches 2.
  4. P, electrical discharge machining (EDM): a shaped electrode (die sinking) copies its form into the work, so a deep square blind cavity in steel suits it, with no cutting force on the shape. P matches 3.
  5. Q, laser beam machining (LBM): a focused laser cuts thin sheet at high speed along a programmed profile. Q matches 4.
  6. Result P-3, Q-4, R-1, S-2: option (A).

Check: a water jet could also cut thin steel, but item 2 can go only to the jet (a laser would scorch food), which leaves item 4 for the laser.

Where this shows up in industry

Laser cutters profile thin steel sheet in sheet-metal shops, water jets cut food, foam and gaskets without heat, and die sinking EDM makes deep blind cavities in mould and die steel. Chemical machining makes thin etched parts such as shims and fine meshes, with the undercut allowed for in the mask artwork.

GATE 2026 · PI · Q.42MCQ · 2 marksNon-traditional machining: ECM, EDM, LBM and jets

Match laser, abrasive waterjet, ion beam and mechanical milling with their removal mechanisms

Which ONE of the following options CORRECTLY matches the machining process and associated predominant material removal mechanism?
Advanced machining processPredominant material removal mechanism
PLaser beam machining1Impact based erosion
QAbrasive waterjet machining2Sputtering
RIon beam machining3Melting and vaporization
SMechanical milling4Shearing
  1. (A)P-1; Q-2; R-3; S-4
  2. (B)P-3; Q-1; R-2; S-4
  3. (C)P-4; Q-3; R-2; S-1
  4. (D)P-1; Q-3; R-4; S-2

Answer: (B) Official key: B

  1. Rule: each advanced process removes material by one dominant physical mechanism. Name the energy form first, then the mechanism.
  2. P, laser beam machining: a focused beam heats the spot far above the melting and boiling points, so the material melts and vaporises. P goes with 3.
  3. Q, abrasive waterjet machining: a jet of water at very high pressure carries hard abrasive grains that strike the work, so the material is removed by impact based erosion. Q goes with 1.
  4. R, ion beam machining: energetic ions in a vacuum knock atoms off the surface one layer at a time, which is sputtering. R goes with 2.
  5. S, mechanical milling: the cutter edge removes chips by shearing the work material. S goes with 4. This leaves the match P-3; Q-1; R-2; S-4, which is (B).

Trap: laser and abrasive waterjet are both jet or beam processes, but one is thermal and the other is mechanical. We stored the true pairing for each of the four processes and tested every option: (A) fails on P, Q and R, (C) on P, Q and S, (D) on P, Q, R and S; only (B) passes.

Where this shows up in industry

Laser cutting of sheet and drilling of cooling holes in turbine parts, abrasive waterjet cutting of stone, composites and thick plate, and ion beam thinning of optics and wafers are chosen on exactly this basis: thermal damage is acceptable with a laser, avoided with a waterjet, and nanometre control comes from ions.

GATE 2026 · PI · Q.53NAT · 2 marksNon-traditional machining: ECM, EDM, LBM and jets

Time for a 1 kW, 0.1 mm laser beam with 10% absorption to melt tungsten carbide from 32 degrees C

In laser beam machining, the time () required for the material to attain the melting temperature from a room temperature () of 32 °C is expressed by the following expression,

where is thermal diffusivity, is melting temperature, is thermal conductivity, is heat flux.

If a uniformly distributed 1 kW power laser beam with a beam diameter of 0.1 mm is used for machining tungsten carbide, and 10% of beam absorption is assumed, the time is ______ s (rounded off to one decimal place).

Note: Thermal properties of tungsten carbide: melting temperature = 3400 °C; thermal conductivity = 2.15 W/cm-°C; diffusivity = 0.79 cm2 s-1; assume .

Answer: 32.1 μs Official key: 31 to 33

  1. Rule: the heat flux is the absorbed power divided by the beam spot area. Work in one unit system: here W, cm and s, since is in W/cm-°C and in cm/s.
  2. Spot diameter , so the area is .
  3. Absorbed power , so .
  4. Temperature rise . Then , and .
  5. , so the answer is 32.1.

Check: the same calculation in metres (W/m, = 215 W/m-°C, ) gives the same time. Trap: forgetting the 10% absorption makes ten times larger and a hundred times smaller, 0.32 s.

Where this shows up in industry

Laser cutting and drilling of hard carbide and ceramic parts relies on the surface heating to melting within microseconds. Shops pulse the beam so that the surface reaches melting and vapour without the heat spreading into the bulk.

GATE 2024 · PI · Q.40MCQ · 2 marksCNC, CAD and robotics

Match 3-DOF robot configurations (Cartesian, cylindrical, spherical, articulated) with their joint types

Match the configurations of the listed 3 degrees-of-freedom industrial robots with the type of joints.
ConfigurationType of joints
PCartesian1One prismatic and two rotary
QCylindrical2Three rotary
RSpherical3Two prismatic and one rotary
SArticulated4Three prismatic
  1. (A)P-3, Q-1, R-2, S-4
  2. (B)P-4, Q-3, R-1, S-2
  3. (C)P-4, Q-2, R-1, S-3
  4. (D)P-3, Q-1, R-4, S-2

Answer: (B) Official key: B

  1. A robot joint is either prismatic (P), which slides in a straight line, or rotary (R), which turns about an axis. A robot with 3 degrees of freedom has three joints, and its name comes from the shape of the space its wrist can reach. The joints are named from the base outwards.
  2. P, Cartesian: three sliding axes at right angles (PPP), so the reach is a box. P goes with 4 (three prismatic).
  3. Q, cylindrical: a rotating base, then a vertical slide and a radial slide (RPP), so the reach is a cylinder shell. Q goes with 3 (two prismatic and one rotary).
  4. R, spherical (polar): a rotating base, a pivoting shoulder and a telescoping arm (RRP), so the reach is part of a sphere. R goes with 1 (one prismatic and two rotary).
  5. S, articulated (jointed arm): rotating base, shoulder and elbow (RRR), like a human arm. S goes with 2 (three rotary).
  6. The set is P-4, Q-3, R-1, S-2: (B).

Check: the four types were encoded as joint strings, counted into prismatic and rotary joints, and compared with every option; only (B) matches. Trap: swapping cylindrical and spherical, since both have one rotary base joint; count the sliding joints instead (two for cylindrical, one for spherical).

Where this shows up in industry

Cartesian gantry robots load machine tools and run pick-and-place lines, cylindrical arms serve die-cast and injection moulding machines, and articulated six-axis arms do welding, painting and machine tending. The first three joints of an articulated arm are the RRR positioning arm that this question names.

GATE 2024 · PI · Q.56NAT · 2 marksCNC, CAD and robotics

CNC quarter-circle slot A(0,0) to B(10,10): feed along y at the point where the x feed is 6 mm/min

A CNC milling operation is carried out by moving the tool from the point A to point B in anti-clockwise direction to cut a slot of quarter circle with center at C, as shown. The coordinates of the points A and B are (0,0) and (10,10), respectively. All dimensions are in mm. If the feed rate at point P along x-axis is 6 mm/min, then the feed rate (in mm/min) at point P along y-axis is _____________ . (Rounded off to 1 decimal place)
Quarter circle slot cut anticlockwise from A at the origin to B at (10, 10) with its centre C at (0, 10); point P on the arc is 6 mm from the y axisxyABCP6 mm

Answer: 4.5 mm/min Official key: 4.5 to 4.5

  1. In circular interpolation the controller moves the tool along an arc by changing the two axis speeds together. The feed along the path is always tangent to the arc, so the ratio of the two axis feeds equals the slope of the tangent at that point.
  2. The arc has centre C at (0, 10) and passes through A(0, 0) and B(10, 10), so the radius is mm. The circle is .
  3. Point P is at mm: , so mm (the lower branch, since the arc starts at A). P is (6, 2).
  4. Differentiate: , so . The feeds are in the same ratio: .
  5. 4.5 mm/min, equal to the key 4.5 to 4.5.

Check: the arc was swept in 0.001 degree steps; falls at 36.87 degrees from A, where the tangent ratio is , and a finite-difference slope of the path gave the same 4.5 mm/min. The resultant feed along the arc is mm/min. Trap: inverting the ratio (using ) gives 8.0 mm/min; at P the arc is still flatter than 45 degrees, so the y feed must be smaller than the x feed.

Where this shows up in industry

CNC controllers split the programmed feed between the axes on every arc and fillet (G02 and G03 moves), so that the tool moves along the curve at the set speed. Programmers check that the axis feed limits are not exceeded where the arc is steepest.

GATE 2025 · PI · Q.24MCQ · 1 markCNC, CAD and robotics

Match a CNC turning centre and a vertical machining centre with their minimum number of axes

Match the following with reference to the CNC machine and its minimum number of axes available in the machine.
Type of CNC MachineMinimum number of axes
PTurning center (CNC Lathe)i3
QMachining center (CNC Vertical milling)ii2
iii4
  1. (A)P – i, Q – ii
  2. (B)P – ii, Q – i
  3. (C)P – i, Q – iii
  4. (D)P – ii, Q – iii

Answer: (B) Official key: B

  1. An axis of a CNC machine is a direction of controlled motion. The minimum count depends on the machine's basic kinematics.
  2. A turning centre (CNC lathe) cuts a part that rotates, with the tool moving across it and along it. Two slides are enough: X (across, sets the diameter) and Z (along the spindle). Minimum axes = 2, item ii.
  3. A vertical machining centre moves the cutter and table in three mutually perpendicular directions, X, Y and Z, to mill a pocket or a 3D surface. Minimum axes = 3, item i. A fourth (rotary) axis is an option, not the minimum.
  4. So P is ii and Q is i: option (B).

Check: the rotating spindle of a lathe is a speed, not a positioning axis, so it is not counted as the third axis. Item iii (4 axes) is the extra distractor.

Where this shows up in industry

Two-axis lathes make shafts and bushings, while three-axis vertical machining centres are the standard for plates, moulds and housings. Adding a fourth rotary axis or a live-tool turret is how a shop avoids a second set-up on the same part.

GATE 2025 · PI · Q.40MCQ · 2 marksCNC, CAD and robotics

New cutter position after 20 s on a straight CNC slot of slope 1.25 from P(10, 5)

A CNC vertical milling is used for cutting a straight line slot in x-y plane. Cutter is located at point P. The slope of the straight line created by the cutter is 1.25. Feed rate of x-axis is 120 mm/min. The new position of the cutter after 20 seconds is
Axes x and y with the cutter start point P at (10, 5) mmyxP (10, 5)All coordinates are in mm.
  1. (A)(50, 55)
  2. (B)(60, 50)
  3. (C)(60, 48)
  4. (D)(100, 80)

Answer: (A) Official key: A

  1. In linear interpolation the controller drives the axes together so the tool stays on the straight line. Each axis moves at its own feed: the x feed is given, and the y feed is slope x feed so that .
  2. X feed mm/min mm/s. In 20 s: mm.
  3. Y moves mm in the same time (y feed mm/min).
  4. The cutter started at P(10, 5), so the new position is mm. A step-by-step simulation of the two axes gave (50.0, 55.0).

Trap: reading 120 mm/min as the speed along the slot gives (35.0, 36.2), which is not an option. The paper states that 120 mm/min is the x-axis feed, so the path speed is mm/min. Adding the displacement to the origin instead of P gives (40, 50), also absent.

Where this shows up in industry

This is the arithmetic behind a G01 linear move: the controller splits the programmed feed over the axes so that every axis reaches the end point at the same moment. Programmers check that the resulting axis feeds are inside the machine's limits.

GATE 2026 · PI · Q.27MSQ · 1 markCNC, CAD and robotics

Which of IGES, STEP, NDC and STL are established CAD geometry data transfer formats

Which ONE or MORE among the options given is/are well established format(s) of data transfer used in geometrical modelling related to computer aided design (CAD)?
  1. (A)IGES
  2. (B)STEP
  3. (C)NDC
  4. (D)STL

Answer: (A) and (B) and (D) Official key: A;B;D

  1. Rule: CAD systems from different vendors keep geometry in their own native files, so work is passed between them in a neutral file format: a published standard that every system can read and write.
  2. (A) IGES, the Initial Graphics Exchange Specification, is the older ANSI standard for curves, surfaces and drawing entities. Established, so it is in.
  3. (B) STEP, ISO 10303, is the current standard for solid models and product data (AP203, AP214, AP242). Established, so it is in.
  4. (C) NDC means normalised device coordinates. It is a screen coordinate system used in computer graphics to make drawing independent of the display, not a file format for transferring a model. Out.
  5. (D) STL, stereolithography, stores the surface as a mesh of triangles. It is a long established exchange format for 3D printing and rapid prototyping, and every CAD system exports it. In. The answer is (A), (B) and (D).

Trap: NDC looks like an acronym of the same kind as IGES and STEP, but it names a coordinate system, not a file. We stored each option as a format or not, with its reason: the passing set is A, B, D.

Where this shows up in industry

When a supplier sends a casting or a machined part to a customer who uses a different CAD package, the drawing goes as a STEP file for the solid model, IGES for older surface data and STL for a quick 3D print of the shape.

GATE 2026 · PI · Q.48MSQ · 2 marksCNC, CAD and robotics

Which 4 by 4 homogeneous matrices involve a rotation about the Y axis by an angle theta

Which ONE or MORE among the following homogeneous representations in robotics involve(s) rotation about Y-axis by an angle ?
  1. (A)
  2. (B)
  3. (C)
  4. (D)

Answer: (C) and (D) Official key: C;D

  1. Rule: a homogeneous transformation is a matrix. Its top-left block is the rotation and its top-right column is the translation. The basic rotations are , and .
  2. Rotation about the Y axis leaves the Y coordinate unchanged, so the second row and column are , and the other four entries mix X and Z: . The is in the bottom left.
  3. (A) has 1 in the third diagonal place, so Z is unchanged: rotation about Z. (B) has 1 in the first diagonal place, so X is unchanged: rotation about X.
  4. (C) matches exactly. (D) has the same rotation block as (C), with a translation of in the last column. A rotation followed by a shift still involves the rotation about Y, so (D) counts. The answer is (C) and (D).

Trap: the sign pattern. For Y the sits at the bottom left, the reverse of and , where it is at the top right. A matrix with the signs swapped would be . We built all three rotations numerically and compared each option with for four angles: (C) and (D) equal , (A) equals , (B) equals .

Where this shows up in industry

Robot controllers chain these matrices to turn joint angles into the position and orientation of the tool. The offset column is the link length, which is why a wrist rotation about Y comes with a translation to the next joint.

GATE 2026 · PI · Q.52NAT · 2 marksCNC, CAD and robotics

Y positional error at X = 180 mm for a 45 degree CNC slot when Y velocity is 5% low

A linear slot is to be milled in a single pass from the point (0, 0) to (180, 180) on XY plane by a CNC machine. The actual velocity along the Y-axis is 5% less than the intended value. The programmed feed rate along the intended slot is 150 mm/min.

The magnitude of the positional error along the Y-axis when the X-coordinate reaches 180 mm, is ______ mm (in integer).

Note: All coordinates are in mm.

Answer: 9 mm Official key: 9 to 9

  1. Rule: in linear interpolation the controller splits the programmed feed along the path into axis velocities in the ratio of the axis travels. The slot runs at 45 degrees, so .
  2. X is on target. Y runs at 95% of its intended velocity: .
  3. X reaches 180 mm after .
  4. By then Y has moved instead of 180 mm. Positional error along Y . The answer is 9 mm.

Shortcut: both axes travel for the same time, so Y falls short by 5% of its own travel, ; the feed rate of 150 mm/min is not needed. Common slips: taking 5% of the feed gives 7.5; taking 5% of the 254.6 mm path length gives 12.7. We stepped through the motion in time and read the Y error at X = 180 mm: 9.0000 mm.

Where this shows up in industry

A velocity mismatch between axes turns a straight programmed line into a tilted or bent one. This is why CNC commissioning checks axis gains and servo matching, for example with a ballbar test, before cutting slots, chamfers and angled faces.

From GATE prep to a machining, CNC programming or manufacturing engineering career

Talk to a counsellor.

Talk to a career counsellor

Free 20-minute call. We'll map the right course to where you want to work.

By submitting you agree to our Terms and Privacy Policy.

Talk to a career counsellor

Talk to a career counsellor

Free 20-minute call. We'll map the right course to where you want to work.

By submitting you agree to our Terms and Privacy Policy.