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Planning the Rear Door Model and Building Its Flange in NXCAD

A free lesson from Skill-Lync's Automotive BIW Design and Development Part 2 using NXCAD course, on Grow by Skill-Lync · Last updated 16 Nov 2026 · Session: “Week 1 Backdoor Session 3”

What will you learn in this free Automotive BIW Design and Development Part 2 using NXCAD lesson?

The instructor lists the order of modelling steps for the rear door, from flange and surface to embosses, hem and windshield. The lesson then starts the NXCAD work: working surfaces from the styling, points and datum coordinate systems, and sketched flange cross sections with 35 mm and 25 mm lengths.

  • Order of features for modelling the inner panel
  • Building working surfaces without altering the styling
  • Datum coordinate systems for flange cross sections
  • Constraining flange sketches and using feature groups

What comes after lesson 3?

Later in Skill-Lync's Automotive BIW Design and Development Part 2 using NXCAD course (paid): lesson 4, Week 2 Backdoor Session 1; lesson 5, Week 2 Backdoor Session 2; lesson 6, Week 2 Backdoor Session 3. The full course has 42 lessons (23 h 41 min of video); see the course overview or its price and syllabus.

Lesson transcript

Machine transcript of the lesson audio (lightly cleaned). Technical terms may contain errors; the video is the reference.

Hey guys, welcome back to our course on advanced automotive body in white design. In week 12 and 13 of our course, we're going to look at how to design the rear door or the tailgate using Simulink, Simscape software. Before we actually move into designing or modeling the rear door and its components, we just wanted to give you a heads up as to what we're going to do and the sequence of the various features that we're going to design. So before that, first let me hide all these. I'll hide the spoiler, windshield, outer, upper and outer clover.

So here we have the inner panel. First what we'll be doing is we'll be creating this flange. Hope you can see the flange here. Yes, that will be the first thing that we'll do. Following which we'll create the surface. The entire thing is going to be done in one half and then we're going to do a mirror geometry. So please make a note of it. After we complete the flanges and we'll be creating the surface, this big surface here. We'll do the touch-ups for this areas.

And then we'll move on to create the embossers. Also the cuts, the holes in the edge blends. Then we'll move on to create the holes for the reinforcements of the hinge as well as the gas stay. And then also we'll create this provision here which is going to be used for the outer panel and the inner panel hem and also at this region they're going to be braced together. After that we'll be creating these embosses. These embosses as well. This is for the drip panel and once we do the mirror geometry as you can see only this feature here is not going to be symmetric about the mid plane.

So only after we create the mirror geometry we'll be creating this feature here. This is the emboss for the wiper motor. I haven't shown these but you have to do these. You have to create all the reinforcements. You'll have the gas stay reinforcement, the hinge reinforcement and also you have to create the emboss as well as the reinforcement for the latch and striker. Here you'll be given the components. So you have to create mating holes and mating embosses. Mating surface faces in fact. We'll move on to the outer upper and the outer lower. So I unhide the outer upper and the outer lower.

So all the sheet bodies are visible. I'll hide them. Also hide the retems, curves and sketches. Now as you can see the outer panel is not just styling. It has the outer lower is just styling. So it's just that the outer upper is not just styling. So here we have to create this provision for placing the windshield and also the rubber. So accordingly we'll be designing that and these embosses I haven't shown. These you have to create. according to the snap fit that is required for the spoilers. You have to create mating embosses on both the spoilers and the outer upper. After this you have to hem both the outer upper and the outer lower with the arena panel. As you can see the hem. This is how the hem ends. Also you have to give corner reliefs. Here there are there's no corner relief here but you have to give corner reliefs for the hemming.

So after this we'll move on to design the windshield. So once the windshield is done. As you can see we have the headliner as well as the glass. The windshield glass. Also make sure that the headliners cover the steel parts. I mean the steel flanges. In the part that I've designed I wouldn't have shown them. It is just for reference. So you have to make sure that in both these regions. So you have to make sure that in both these regions and all around the headliner covers the sheet metal. After this we'll move on to the spoilers. The spoilers won't be shown here. It's a challenge for you to actually create the spoilers.

Okay. Yes the spoilers are going to be plastic parts. So a simple thicken on the inside would be fine. But you have to create the embosses. Let me show you. Yes as you can see you have embosses on the outer upper and the spoilers as well. So you have to create this. Make sure you have enough mounting points for the spoilers to snap on perfectly. So that's it. Now let's move on to the modeling section in NXCAD. So this is a styling that you'll be getting from us. So here you have the outer upper, the outer lower. You also have the styling for the back door windshield glass. As you can see all these three are integrated together with a spoiler. So all these four together make the styling for the back door. So we're going to derive the inner panel from this and we're going to work on it.

So let's create the working surface for our outer panel. First I'll do an untrim operation on this to get. To extend it till the outer spoiler and to fill this hole. I'll discard this region. Hit OK. Now if I turn back. Yes there we have the surface that we need. Now I'll hide the spoilers and the outer upper. Okay so for that we'll trim this sheet with respect to the windshield styling to get the hole. So this is this will be the part. I mean this hole that I'm selecting is going to be the place where the windshield glass is going to come. And the border that you see is going to be the headliner for the windshield. So this region will discard and the orange I'll keep. If I hide the BD styling I will be able to see the hole. So this is the rear visibility criteria for any passenger sitting inside.

Now I'll unhide the spoiler. Go to offset surface. Since it was a tangent surface the entire thing got selected. I did an offset at zero. I'll hide the styling now. Now I have to trim it with respect to the offset surface that I created. As you can see there's an extra region there. I go to trim sheet. And select the edge. Make sure you select all the edges in case of tangent curves or single curves. And if check if the stop it intersection is selected. So this will be the region that I'll keep. And the other region I'll discard. So this I'll keep.

Let me zoom in and see. So I'll do an offset surface of the lower. I mean outer lower again. So that we can hide the outer lower as well. At zero mm. Click ok. Now I'll hide the styling. So here we have. The working surfaces. That is the working outer panel surface. From this we'll derive the inner panel. As you can see it is almost symmetric about the mid plane. So let me select all these three offset surfaces. So let me select all these three offset surfaces. And select the mid plane. We're going to work on the left hand side. So this side I'll discard. We'll put all of these into one feature group. I'll rename it as BD working surface.

Is it ok. So if we're going to make any changes to these surfaces. It's going to be only the working surface and not the styling. We'll be deriving our surfaces from the styling in the later stage. But we will not make any changes to the styling. To make sure that we obey the styling. And we don't deviate from what the styling team has given us. Now. We're going to create rate mcs wires all around the styling. But for that we need a point. So. This won't work properly because the point is getting created on the face. So. Since I'm going to do it throughout. First I'll create the points. All around the enclosure. And then we'll create the flange. Ok. I'll go to point on curve. So on the top region we're going to have two cross sections. So I'll select here. This will be my first.

Apply. Here I have my second. Here again we'll have two more cross sections. Because this is the narrow region. And here there's a transition towards the curves where the rear lighting is going to come. Ok. So for this. Let me see. It's going to take this shape here. So. We'll have two cross sections here as well. I'll select this edge. So this will be my fifth cross section. I mean fifth point for the cross section that I'm going to create here. And six and seven. Can actually create one more cross section there. If you want. If you want a perfect curve. So here just to show you how it's done. I've taken seven cross sections. Now we'll go to datum cs wire and we'll create it. So I'll select the point. I'll select the x and the y axis. We'll reverse the direction. So that we get a plane.

So with this plane. So with this plane I'll be creating sketches all around the enclosure of the outer. Panel. Again, I'll select my X and Y, reverse direction and select OK. Similarly, you're going to create CSYS at all the 7 or 8 points that you have and based on those CSYS, we're going to create sketches. Those are going to be the cross sections for our flange. As you can see, I've skipped the video to the lower panel, the lower outline in fact. So, let me show you a look around. Yes, so I have 7 to 8 CSYS here. What I want you to do is create them based on what you see here.

Now, we'll put all these datum coordinate systems and these points into one feature group. We create a lot of feature groups because this is for your clarity and you also have to do this when you're working in industry because anyone who views your design should be able to break it down into parts and understand what has been done and in what sequence they've been done. Now, we'll do sketches all around and we'll create every single cross section and then connect them to form the first flange.

For the ceiling. Now, I selected this plane. I'll select this direction and hit OK. It has given me the other view. I'll change the direction. Snap to the oriented view. Now, now I want you to pay close attention here because you're going to create the other sketches based on what I'm doing here. So, we'll first offset this curve. Before this, I took a reference. Now, we'll offset to 2 mm in the downward direction. Double clicking on the arrow will work. Now, let me do the sketch. So, this is based on what you saw in the cross section there. You can create your own master section. Here, the values are obviously random. I'll be constraining the sketch to make them fully constrained which you have to do again.

So, the angle here we have 120 degrees and this flange is going to be 35 because we have a lot of space here. So, this will reduce to 25 in the corners and in the side flange where we have the windshield. So, make sure you make a note of it. So, the distance from the outermost point again this is going to be 35. So, here I'm just creating the first step of the flange and the cross section. Now, similar to this we're going to create for the second CS wire as well. Too many CS wires here are confusing. So, I'll hide them all. So, I'll hide these four first. Now, so I'll select this plane. I'll do a sketch at 0 mm. This will be my vector. Again, I have to go to the other direction because the software gave me the wrong direction.

Now, the same is going to be done here because the cross section follows throughout. As you can see there there was the edge so I took an offset but here I have to create the intersection curve between the plane that is perpendicular to this face. So, I'll select the plane and now I'll select the face. I'll get the intersection curve. Now, I'll go back to sketch. Select the plane and select the vector. This will be my horizontal vector. I'll take another view. As usual we'll do an offset for 2 mm and from this offset we'll create the cross section.

So, this line I'm creating parallel to the previous offset curve that I had. Again, I'll start with the angle. This is the position the sketch so that it doesn't float away and then this will have 35 mm. Again, the depth I have 45 and then this again will have 35 mm. So, we have the third datum coordinate system here. As usual we'll get the intersection curve between the plane and the face. Select the face here. Okay, there we have the intersection curve. We'll do an offset with this curve and then create the sketch from that. Again, these vectors and the planes that I'm doing are just my idea of how I'm going to move on with the design idea.

You can have your own vectors and your own sketches. They just have to follow and satisfy the basic rules. I mean the thumb rules that we saw in the earlier videos. Okay, here as you can see the flange length is not going to be as big as what we saw in the previous two cross sections. It is going to be a little less. That is, we've already talked about this. It's going to be a minimum of 25. So, I'll maintain the angle. It's 10 degrees less than what we saw in the previous cross sections. And here, in order to hem, we'll have a minimum of 12 mm. And this is going to be the minimum value which is going to be 25 mm. The depth will maintain.

Let me show this view. Yes, we're going to have another law extension here. So, at that time, we have to extend anyway. So, I'll reduce it to 35. I'll create the same for the next coordinate system. That is the fourth cross section. So, that's one, two, three, and we have to go to our fourth. I'll unhide this. I'll first create the intersection curve. Every time the software gives you a snap view of the sketch, you can always change it because these are critical areas and we cannot work with the oriented view that the software gives us. So, I'll just take my own view and do the sketch.

You can always span, rotate and then see if your sketch is proper. So, for this, you have to take the point to point dimension. The dimensions here are going to be similar to what we saw in the previous cross section. So, I'm not repeating the values here. Finish sketch. So, here we have four cross sections. The remaining cross sections, we need not have the law extension line. We can just have just one line that indicates where it's going to be positioned. And to constrain it, we have to give dimensions.

Let me work with this coordinate system. I'm going to create a datum plane from this at a particular distance. So, instead of the law extension line that I talked about previously, here we give the value. This mentions the depth of the line that we are going to create. Do a sketch with this data plane at zero mm. Look for the vector. I need a horizontal line. Yes. Okay. Here we create the sketch. It's just going to be one simple line. And that line has to be at a distance from the edge. I'm having a horizontal line. I'll just enter.

As you saw, I just press enter after selecting the outer dimension. This is to position the sketch. So, it doesn't fly away from our view. Now, it's going to be 25 mm in width. And you have to position it with respect to the outer edges. That is, we must have a minimum of 15 mm for hemming. So, make sure you have that. Let's go to analysis and measure the distance between these two points. I'll select point and then select this point. Here, let me select the edge. It won't show the exact value. Let me select this point that we created.

Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge. Let me select the edge I'll go to measure, point, and you can see, okay, it is giving me the minimum distance to be more than 25. So that will be more than 35. In fact, it's somewhere around 60. So that's fine. So you have to position it completely. I'm just leaving it at that stage. I'll unhide the remaining datum curves. I'll hide the previous one. Yes. Now here, we're going to do the same.

We have to create a datum plane here also. Here we'll mention the depth. I'll hit OK. And we'll sketch with respect to this plane. I'll take this view. And now start the sketch. At first, I'll randomly create a line. And then I'll position it. Yes, I'm just showing it where it should be actually, but it's not constrained. So I'll just go to manual dimensions. And I have to change to vertical. I'll go to rapid dimension. Okay, first we'll do the horizontal. I hit zero. And this is going to be 25. So now we have two cross sections here. We still have two more. I'll unhide them. We're going to do the same here, but just in the horizontal direction.

So once we do our law extensions and bridge curves and the story surfaces, once we connect all these, you'll understand why we created so many cross sections and so many sketches. Here we're going to have a vertical line. Again, this has to be at a minimum distance of 35 mm from the bottom. Please make sure that. And also the flange length is up to you. It can be 25 or 35. Since we changed from 35 to 25 the corners, I'm still maintaining the 25 mm distance.

Again, I'll create a D-templine and create the sketch here as well. I'll reverse the direction. As you can see, there's a curvature to the lower outer panel. So we have to follow that and change the distance. Okay. I'll do a sketch here. I'll reverse the direction for my horizontal vector. I can't reverse the Y. Yes. So here, we'll do the scheme sketch. We'll constrain it with respect to the previous sketch. So with respect to the edge, it is going to be at a minimum of 45 mm.

And this is going to be 25 mm. I'll hide all these datums first. So the datum planes, then the coordinate systems. So as you can see, the various cross sections that we just created. I'll hide this extension line. So here we have one, two, this is the third, and then the fourth. The fifth, sixth, seventh, and eighth are just flanges and the depth is mentioned whenever we create the datum plane. So in the next video, we'll create the law extensions for these and then we'll create the entire flange based on these cross sections.

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